& Construction

Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
& Manufacturing

Professional CAD/CAM tools built on Inventor and AutoCAD
Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
Professional CAD/CAM tools built on Inventor and AutoCAD
Transcript
00:02
In this lesson, we'll use 3+2 axis position drilling.
00:07
After completing this lesson, you'll be able to create a 3+2 drilling operation and use duplicate to copy an operation.
00:16
In Fusion 360, we want to carry on with our multi-axis positioning design.
00:21
From here, we've already done all of our 2.5 and 3-axis operations from the top with the exception of clearing out this center pocket.
00:28
That's something that I will come back to a little bit later.
00:31
But right now we want to dive into multi-axis, which is the intention of this course.
00:36
Now the course itself is talking about not only simultaneous multi-axis but 3+2, 3+2 is probably the most common form of multi-axis machining,
00:48
where we rotate a part in five axes to get to a correct orientation to use a 2.5 or 3-axis operation.
00:56
So to get started with this process, we want to understand how to apply that to drilling holes.
01:02
So to get started, we're going to be using drilling.
01:06
From here, we need to select the appropriate tool, and I want to note that inside of this document in multi-axis positioning,
01:14
we have operations that use tools such as tool number one, which is our spot drill.
01:19
But then we also have tool number one, which is a face mill.
01:22
There's a lot of duplicate tool numbers and tools that we aren't using.
01:26
So we're going to right click on multi-axis positioning and remove the unused tools.
01:32
We'll choose to delete those.
01:33
So now we only have access to the tools that we've already selected or we can go to our cloud library and make any selections needed.
01:41
So using tool number one, our spot drill will move on to our geometry section.
01:46
The first thing that we typically do is select a hole that we want to drill.
01:50
Now, in most cases this will be oriented based on the Z coordinate of our WCS.
01:55
However, we want to drill the side hole but notice that it's not allowing me to select any faces or edges
02:02
and that's because the orientation of those is not in line with our Z coordinate system.
02:07
So in order to use 3+2, we need to first use this tool orientation option and select the orientation of our Z axis.
02:17
This can be done by selecting the center of the hole, or we can select a face that puts Z normal to.
02:24
We also might have to flip the Z axis, but in this case, notice that once we flip it, Z is in the same orientation as the whole as we want to drill.
02:35
So now that we have our coordinate system based on the whole that we're looking at, we can select the hole face.
02:41
This is going to be the center, and then we need to determine where exactly we want to drill to.
02:47
So from our heights, I'm going to use a selection, grab this upper edge and then have a negative offset value.
02:54
In this case, I'm going to say -.05. From there, I'll say okay and allow it to calculate this spot drill operation.
03:03
So here you can see that the tool is coming in from the side.
03:07
The next thing that I want to do is I want to duplicate that because I already have all the orientation selected,
03:14
and then I want to create an operation that allows me to drill that hole.
03:19
Now, in most cases, you would probably start with a smaller bit and then move your way up to a larger bit or in the case of this hole,
03:26
we could actually go in with an end mill and treat it as a pocket or a board.
03:31
But starting out with the 3+2 drilling is a great introduction into this multi-axis machining.
03:37
So, first, we need to select a different tool.
03:40
From our multi-axis tool library, we're going to be using tool number three, which is a half inch drill.
03:46
From there, we'll go to our geometry and the orientation is still correct.
03:51
So I don't need to make any additional selections here.
03:54
However, the height is going to be based on a different edge selection.
03:58
I need to go all the way to the backside of this hole.
04:01
So I'm going to select the back edge, and then I'm going to use the drill tip through bottom.
04:07
I want to delete the offset value or reset it to zero, and I'm going to use a positive breakthrough value.
04:14
When we're taking a look at using breakthrough with drill tip through bottom, we need to enter a positive value, in this case .1.
04:22
When we're using an offset value, it's negative based on our coordinate system.
04:27
So now that we have that selected, we want to go to our cycle and make sure that we're either using a partial retract or a deep drilling cycle.
04:35
I'll use all the default values and I'll say ‘okay’.
04:38
Now we're drilling the hole as well as doing that spot drill operation.
04:43
From here, I want to move that over to this other side of the design.
04:48
We can't simply create a circular pattern or pattern to move around to the other positions on the design,
04:54
just because the orientation and the symmetry of the model is not going to allow us to do that.
05:01
So I want to make sure that I create operations that can be duplicated.
05:05
First, I'm going to start by taking drill number four.
05:08
The rapid out, which is our peck drill.
05:10
I'm going to right click and duplicate it.
05:13
I want to make sure that we understand that when we duplicate it, it places it directly after it in the browser.
05:19
So the one at the end is actually our drilling operation.
05:22
So before we go any further, I'm going to drag my duplicate drill, and then I want to edit this operation.
05:32
First thing we'll do is go to our geometry, and we're going to reselect the tool orientation axis.
05:38
From there, the Z orientation looks correct.
05:40
We're going to reselect the hole face.
05:44
Then for our heights, we need to reselect our edge.
05:48
We grab this edge, and notice that we're at -.05, we can say ‘okay’.
05:55
Now we're peck drilling that side.
05:56
We can go back to our drilling chip breaking operation.
05:60
We can duplicate it. Once again it places it directly after in the browser.
06:04
So we want to make sure we drag it to the end, and then we can edit this operation.
06:11
The tool is going to be fine but once again, we need to reset the Z axis.
06:16
Then we need to reset the whole that we are drilling.
06:19
Next, we need to go to our heights, and we need to reset our selection.
06:24
We will make sure we select the backside, and now all of those settings are correct.
06:32
Now we have our peck drill on the left, our drilling operation and our peck drill on the right and our drilling operation.
06:41
Notice the orientation, we have peck drill on both because we're using the same tool, and then we have drilling on both.
06:48
Typically, you want to be careful about the orientation and tool changes,
06:52
so you want to make sure that you use the tool that's in the holder for as many operations as possible.
06:57
In some cases that might not make as much sense if the part is very large and the tool has to move along distance.
07:04
But now that we have these four operations, I'm going to rename them.
07:09
The first one is going to be spot.
07:11
I'm going to say 5X or 5-axis and position one.
07:15
Then I want to do the second spot.
07:17
I'm going to call this spot 5X, and this is going to be positioned 2 the next one.
07:23
This is going to be drill 5x, and this is position one again.
07:29
And then we have drill 5X position 2.
07:35
Now the names that I gave them are just simple names, so we can understand the positions more so than the actual operation.
07:43
But now that we have these four created, I'm going to select all of them.
07:47
I am going to go to set up and create a new pattern.
07:51
From here, I'm going to create a mirror pattern, and then I need to select the mirror plane.
07:58
Now in my case, I want to make sure that I expand the model, expand the origin folder and then in this case, we're going to be using the XY plane.
08:08
We can order by tool or we can keep the original orientation, and there's an option to override the WCS offset.
08:14
In this case, I don't want to override it.
08:16
I simply want to create that pattern.
08:20
When we take a look at the pattern operation, notice that it hasn't actually created anything for spotting the other side.
08:30
Everything that looks like it has been done, looks like it has been done on this side.
08:35
However, when we select that last operation, you'll notice that it looks like all the holes have been drilled.
08:42
So I'm going to select the pattern, and I'm going to do a quick simulation to see if I can verify what's happening.
08:49
So notice it thinks that it's hitting stock from the outside, that's something that we can address a little bit later,
08:54
but it's spotting all four sides, and then it's drilling all four sides as well.
09:01
So everything looks okay from here, we will have to address the simulation in the stock clearance issues potentially later.
09:08
But now that I have all of these spot drilling and drilling operations, this is a great time for us to save before moving on to the next step.
Video transcript
00:02
In this lesson, we'll use 3+2 axis position drilling.
00:07
After completing this lesson, you'll be able to create a 3+2 drilling operation and use duplicate to copy an operation.
00:16
In Fusion 360, we want to carry on with our multi-axis positioning design.
00:21
From here, we've already done all of our 2.5 and 3-axis operations from the top with the exception of clearing out this center pocket.
00:28
That's something that I will come back to a little bit later.
00:31
But right now we want to dive into multi-axis, which is the intention of this course.
00:36
Now the course itself is talking about not only simultaneous multi-axis but 3+2, 3+2 is probably the most common form of multi-axis machining,
00:48
where we rotate a part in five axes to get to a correct orientation to use a 2.5 or 3-axis operation.
00:56
So to get started with this process, we want to understand how to apply that to drilling holes.
01:02
So to get started, we're going to be using drilling.
01:06
From here, we need to select the appropriate tool, and I want to note that inside of this document in multi-axis positioning,
01:14
we have operations that use tools such as tool number one, which is our spot drill.
01:19
But then we also have tool number one, which is a face mill.
01:22
There's a lot of duplicate tool numbers and tools that we aren't using.
01:26
So we're going to right click on multi-axis positioning and remove the unused tools.
01:32
We'll choose to delete those.
01:33
So now we only have access to the tools that we've already selected or we can go to our cloud library and make any selections needed.
01:41
So using tool number one, our spot drill will move on to our geometry section.
01:46
The first thing that we typically do is select a hole that we want to drill.
01:50
Now, in most cases this will be oriented based on the Z coordinate of our WCS.
01:55
However, we want to drill the side hole but notice that it's not allowing me to select any faces or edges
02:02
and that's because the orientation of those is not in line with our Z coordinate system.
02:07
So in order to use 3+2, we need to first use this tool orientation option and select the orientation of our Z axis.
02:17
This can be done by selecting the center of the hole, or we can select a face that puts Z normal to.
02:24
We also might have to flip the Z axis, but in this case, notice that once we flip it, Z is in the same orientation as the whole as we want to drill.
02:35
So now that we have our coordinate system based on the whole that we're looking at, we can select the hole face.
02:41
This is going to be the center, and then we need to determine where exactly we want to drill to.
02:47
So from our heights, I'm going to use a selection, grab this upper edge and then have a negative offset value.
02:54
In this case, I'm going to say -.05. From there, I'll say okay and allow it to calculate this spot drill operation.
03:03
So here you can see that the tool is coming in from the side.
03:07
The next thing that I want to do is I want to duplicate that because I already have all the orientation selected,
03:14
and then I want to create an operation that allows me to drill that hole.
03:19
Now, in most cases, you would probably start with a smaller bit and then move your way up to a larger bit or in the case of this hole,
03:26
we could actually go in with an end mill and treat it as a pocket or a board.
03:31
But starting out with the 3+2 drilling is a great introduction into this multi-axis machining.
03:37
So, first, we need to select a different tool.
03:40
From our multi-axis tool library, we're going to be using tool number three, which is a half inch drill.
03:46
From there, we'll go to our geometry and the orientation is still correct.
03:51
So I don't need to make any additional selections here.
03:54
However, the height is going to be based on a different edge selection.
03:58
I need to go all the way to the backside of this hole.
04:01
So I'm going to select the back edge, and then I'm going to use the drill tip through bottom.
04:07
I want to delete the offset value or reset it to zero, and I'm going to use a positive breakthrough value.
04:14
When we're taking a look at using breakthrough with drill tip through bottom, we need to enter a positive value, in this case .1.
04:22
When we're using an offset value, it's negative based on our coordinate system.
04:27
So now that we have that selected, we want to go to our cycle and make sure that we're either using a partial retract or a deep drilling cycle.
04:35
I'll use all the default values and I'll say ‘okay’.
04:38
Now we're drilling the hole as well as doing that spot drill operation.
04:43
From here, I want to move that over to this other side of the design.
04:48
We can't simply create a circular pattern or pattern to move around to the other positions on the design,
04:54
just because the orientation and the symmetry of the model is not going to allow us to do that.
05:01
So I want to make sure that I create operations that can be duplicated.
05:05
First, I'm going to start by taking drill number four.
05:08
The rapid out, which is our peck drill.
05:10
I'm going to right click and duplicate it.
05:13
I want to make sure that we understand that when we duplicate it, it places it directly after it in the browser.
05:19
So the one at the end is actually our drilling operation.
05:22
So before we go any further, I'm going to drag my duplicate drill, and then I want to edit this operation.
05:32
First thing we'll do is go to our geometry, and we're going to reselect the tool orientation axis.
05:38
From there, the Z orientation looks correct.
05:40
We're going to reselect the hole face.
05:44
Then for our heights, we need to reselect our edge.
05:48
We grab this edge, and notice that we're at -.05, we can say ‘okay’.
05:55
Now we're peck drilling that side.
05:56
We can go back to our drilling chip breaking operation.
05:60
We can duplicate it. Once again it places it directly after in the browser.
06:04
So we want to make sure we drag it to the end, and then we can edit this operation.
06:11
The tool is going to be fine but once again, we need to reset the Z axis.
06:16
Then we need to reset the whole that we are drilling.
06:19
Next, we need to go to our heights, and we need to reset our selection.
06:24
We will make sure we select the backside, and now all of those settings are correct.
06:32
Now we have our peck drill on the left, our drilling operation and our peck drill on the right and our drilling operation.
06:41
Notice the orientation, we have peck drill on both because we're using the same tool, and then we have drilling on both.
06:48
Typically, you want to be careful about the orientation and tool changes,
06:52
so you want to make sure that you use the tool that's in the holder for as many operations as possible.
06:57
In some cases that might not make as much sense if the part is very large and the tool has to move along distance.
07:04
But now that we have these four operations, I'm going to rename them.
07:09
The first one is going to be spot.
07:11
I'm going to say 5X or 5-axis and position one.
07:15
Then I want to do the second spot.
07:17
I'm going to call this spot 5X, and this is going to be positioned 2 the next one.
07:23
This is going to be drill 5x, and this is position one again.
07:29
And then we have drill 5X position 2.
07:35
Now the names that I gave them are just simple names, so we can understand the positions more so than the actual operation.
07:43
But now that we have these four created, I'm going to select all of them.
07:47
I am going to go to set up and create a new pattern.
07:51
From here, I'm going to create a mirror pattern, and then I need to select the mirror plane.
07:58
Now in my case, I want to make sure that I expand the model, expand the origin folder and then in this case, we're going to be using the XY plane.
08:08
We can order by tool or we can keep the original orientation, and there's an option to override the WCS offset.
08:14
In this case, I don't want to override it.
08:16
I simply want to create that pattern.
08:20
When we take a look at the pattern operation, notice that it hasn't actually created anything for spotting the other side.
08:30
Everything that looks like it has been done, looks like it has been done on this side.
08:35
However, when we select that last operation, you'll notice that it looks like all the holes have been drilled.
08:42
So I'm going to select the pattern, and I'm going to do a quick simulation to see if I can verify what's happening.
08:49
So notice it thinks that it's hitting stock from the outside, that's something that we can address a little bit later,
08:54
but it's spotting all four sides, and then it's drilling all four sides as well.
09:01
So everything looks okay from here, we will have to address the simulation in the stock clearance issues potentially later.
09:08
But now that I have all of these spot drilling and drilling operations, this is a great time for us to save before moving on to the next step.
Step-by-step guide
How to buy
Privacy | Do not sell or share my personal information | Cookie preferences | Report noncompliance | Terms of use | Legal | © 2025 Autodesk Inc. All rights reserved
Sign in to start learning
Sign in for unlimited free access to all learning content.Save your progress
Take assessments
Receive personalized recommendations
May we collect and use your data?
Learn more about the Third Party Services we use and our Privacy Statement.May we collect and use your data to tailor your experience?
Explore the benefits of a customized experience by managing your privacy settings for this site or visit our Privacy Statement to learn more about your options.