Transcript
00:02
create and manage a digital tool library.
00:05
After completing this video, you'll be able to create a digital tool library,
00:09
create a custom digital tool,
00:11
copy and modify a digital tool and define tool parameters.
00:18
Infusion 3 60. We're going to get started with a new untitled document.
00:22
We're going to move to the manufacturer workspace.
00:25
And the first thing that I want to do is change the units in this case.
00:28
What we're going to be doing is we're going to be creating a tool library.
00:31
Infusion 3 60. The tool library is going to be independent of any document.
00:35
So changing the units here isn't really needed.
00:38
However,
00:39
it will affect the units that we see displayed
00:41
at the very basic level in our tool library.
00:44
Note that inside of our tool library there's going to be an all section
00:48
will be documents which will be tools that are used in your current document.
00:51
If you have multiple setups,
00:53
you'll also see them listed here underneath your untitled document.
00:57
We have a cloud library, a local library, the fusion 3 60 samples.
01:01
And at the very bottom we can download vendor libraries.
01:04
It's important to note that if you right click on the library,
01:08
you have the ability to turn the libraries on and off.
01:11
This can be done for individual samples.
01:14
For example, if you're not using any of the metric holders,
01:17
you can right click and you can turn this library off.
01:20
This means that it won't be displayed when you're taking a look at the
01:23
various tools and filtering through the different
01:26
holders inside of the sample library.
01:28
If you want to bring it back, you can always right click and turn that library on.
01:32
We're not going to be going through our vendor libraries in this case,
01:35
but I do think that it's important to explore what tools you
01:38
can download from vendor libraries without having to set them up manually.
01:42
Also note that if you don't see cloud listed inside of your tool library,
01:46
make sure that you go to your user preferences and
01:49
we want to make sure that we do enable them
01:51
from the general section you want to go to manufacture
01:53
and make sure that enable cloud libraries is checked.
01:57
Now let's go back into our tool library and let's take
01:60
a look at how we can create our own library.
02:02
All the tools inside of the fusion 3 60 sample library are read only.
02:07
This means that we can take a look at them and we
02:08
can use them in the current document but we can't modify them.
02:12
What we can do is we can create a library in either our local or our cloud location.
02:17
If you happen to log into fusion 360 from multiple computers.
02:20
It's a good idea that you do use the cloud location.
02:23
There are other places in which you can save
02:25
two libraries as well as post processor data by using
02:28
the assets inside of the data panel but we're going
02:31
to focus solely on the cloud and local libraries.
02:34
We're gonna right click and we can either create
02:36
a new empty library that we want to populate.
02:39
We can create a new folder inside of our cloud library or we can import a library.
02:43
I'm gonna select import and navigate to the three axis
02:46
sample library dot tools that we have with the course.
02:50
Once we select okay notice that now inside of our three access sample library,
02:54
we have a cat 40
03:02
If we expand the cloud library, you can see that three access sample is listed here.
03:06
This sample library only contains this one tool and this holder,
03:10
it's always a good idea that we double check our filters to
03:12
make sure that we don't have any of our filters turned on.
03:15
For example, if you enable milling, you can see that the holder is no longer visible.
03:19
So we want to make sure that any filters
03:21
are cleared and note that we only have our quarter
03:23
end mill and the holder
03:25
in order to create new tools,
03:27
we can either create them from scratch or you can bring them
03:29
in from the fusion 3 60 library or a downloaded vendor library.
03:33
I'm gonna begin by going to the Fusion 3 60 library.
03:37
I'm gonna begin filtering by milling.
03:39
I want to take a look at flat end mills and then I
03:42
want to look for the animals that I need for my specific size.
03:45
In this case we're going to be using a half inch flat and a three quarter flat.
03:50
So as I look through this list, I've got a half inch flat end mill.
03:53
When I select it, notice that there are cutting data presets.
03:57
We have ones for aluminum slotting, roughing and finishing.
04:01
This data is important to review because it doesn't necessarily fit with
04:05
your specific machine or the tool that you're going to use.
04:08
Remember that these are generic tools and their unspecified
04:11
materials and they don't have vendor product links.
04:14
So make sure that you do identify the speeds and
04:17
feeds that you do need to use with these tools.
04:19
But what we're going to do is we're going to
04:21
right click on this tool and select copy tool.
04:25
Go back into our three access sample and we're going to right click and paste
04:29
once again when we do this,
04:31
it's important that we note the filters are going to be active
04:34
and we should clear any filters so we can't see our holder.
04:37
When we take a look at this half inch flat end mill.
04:40
Notice that it doesn't have a tool number
04:43
tool number five is a quarter inch flat end mill.
04:45
Now,
04:46
what we want to do is we want to make sure that
04:47
we edit the properties by right clicking and editing the tool.
04:51
We're going to leave the quarter inch flat end mill as tool number five
04:55
and in the post processor section for our half inch flat end mill.
04:59
We're going to set this at tool number six.
05:02
When we do that,
05:03
the length offset and diameter offset automatically update to six as well.
05:07
It's also important that we take a look at our cutter
05:09
data notice that it's listed as a three flute tool.
05:12
It's going to be using the inch
05:14
unit system and currently the material is unspecified
05:18
if we're using a specific tool such as a car by tool. It's a good idea to specify
05:22
that,
05:23
make sure that the number of flutes is going to match because all
05:26
of these things will affect the overall and use of the tool.
05:30
The diameter is correct at half inch. The overall length at three inch.
05:34
The length below holder is the amount it's sticking out
05:36
below our holder and the shoulder length is one inch.
05:39
This all matches data that we're going to be using
05:42
when we go to the holder section. Notice that by default it's using this cat 40 E. R. 32
05:50
What we can do is we can remove the holder and we can pick a different holder.
05:54
If we have one
05:55
again,
05:56
you can take a look in the three axis samples
05:57
and make sure that you do have the correct holder
05:60
if you want to reassign a holder. What we can do is remove the holder from this,
06:04
we can select and use this holder in its place.
06:07
It's always a good idea to double check the cutting data
06:09
to make sure your length below holder is still the same
06:12
at this point we're going to go ahead and accept this and
06:15
now we've got tool number six are half inch flat end mill.
06:18
We also want to make sure that we have a three quarter flat end mill.
06:21
This is going to be used for us to face and machine the top of our part for this.
06:26
I'm gonna go ahead and hit plus to create a new tool.
06:29
I'm going to select flat end mill and I'm going to
06:32
give it a description of three quarter inch flat end mill
06:37
for the cutter. I'm going to make sure that it is a three flute high speed steel.
06:41
The diameter is going to be 30.75,
06:44
which is going to automatically update the shaft diameter,
06:47
the overall length of three inches, the length below holder of 1.1.
06:51
The shoulder length is going to be one inch and the
06:54
flute length we're going to set as one inch as well
06:58
For the holder. Once again, we want to use that same cap 40.
07:01
It's not strictly required that we are using a holder inside of our tool definition,
07:06
but it is important when we come down to programming our tool paths,
07:10
we want to make sure that the non cutting portion of the tool and
07:13
the holder itself doesn't collide with one machine stock or any of our fixtures.
07:18
I'm gonna set this at tool number four and I'm going to select accept.
07:22
Now we have the tools for our machining or milling applications.
07:26
We want to create the spot drill, the finish drill and the taps as well for that.
07:30
I'm going to go back into my samples.
07:32
I'm going to start looking at whole making category and I want to find a drill bit,
07:37
a spot drill and a tap.
07:38
So I'm going to begin with the spot drill and
07:40
I'm going to find an eighth inch spot drill,
07:42
right click copy tool.
07:44
Go back to my sample, right click and paste the tool.
07:48
Once again,
07:49
the filters are active so you're only going to be seeing the whole making tools.
07:53
Now I want to change from a spot drill to a drill bit.
07:56
We're going to be looking for a 0.201.
07:59
As we scroll down through here,
08:00
we want to make sure that we find the correct
08:02
tool that's going to be used to drill this hole.
08:04
This is the number seven.
08:06
We're going to go ahead and right click and copy this tool and in
08:10
our three access sample we're going to right click and paste the tool.
08:14
The last thing that we are going to need is going to be a right hand tap.
08:18
This is going to be a quarter 20 tap.
08:19
So we want to look through our list, find a quarter 20 tap, right click and copy it.
08:25
Also note that we are able to drag and drop into the three access sample.
08:28
And what that does is it will create a copy of it for us as well.
08:32
This can prevent you from going back and forth
08:34
between the samples and into our current cloud library.
08:38
Once again, make sure that we deactivate the filters.
08:40
We want to assign tool numbers to all these tools,
08:43
I'm going to edit the eighth inch spot drill.
08:46
Go to post process and set this at tool number one.
08:50
We're going to accept that we're going to go to our number seven drill,
08:54
we're going to edit the tool.
08:55
I'm going to set this as tool number two
08:58
and last. I want to go into my quarter 20 tap.
09:02
I'm going to edit the tool and set this as tool number three.
09:06
The tools don't need to be in numerical order.
09:08
They simply need to match however you have them set up inside of your machine.
09:13
It's important to note that the spot drill,
09:15
the drill bit and the quarter 20 tap all have varying levels of detail.
09:20
The tap doesn't contain a holder but the drill and
09:23
the spot drill are using a 40 taper drill chuck.
09:27
So again, it's important to note,
09:28
we want to make sure that these tools can go all the
09:32
way down Down to the bottom of whatever we're machining or drilling.
09:35
Make sure that you validate the speeds and speeds
09:37
that are going to be used in this case.
09:40
Note that in this spot drill,
09:42
the aluminum finishing has a 12,000 rpm
09:45
spindle speed.
09:46
That's going to be too fast for the machine that we're likely going to use.
09:49
And that's something that we would need to adjust.
09:51
This can be done by right clicking and editing the tool.
09:55
We can go to its cutting data,
09:57
make sure that we're on aluminum finishing and we can reduce this value to 8100,
10:02
which should be our limit when we do that.
10:04
It's going to update our surface speed as well as our feed per tooth values.
10:08
The fx next to it is going to tell us that is linked to a parameter
10:12
and those parameters are going to be adjusted
10:15
based on changing just our spindle speed.
10:17
We're going to accept that change and then we're going to close our tool library
10:21
because the tool libraries are saved in the cloud or locally,
10:24
there is no safe option that we need to do.
10:26
Remember that they are independent of our design.
10:29
So the untitled document does not need to be saved
10:32
at this point.
10:33
If you want to make any changes to the tool library,
10:35
go ahead before moving on to the next step
00:02
create and manage a digital tool library.
00:05
After completing this video, you'll be able to create a digital tool library,
00:09
create a custom digital tool,
00:11
copy and modify a digital tool and define tool parameters.
00:18
Infusion 3 60. We're going to get started with a new untitled document.
00:22
We're going to move to the manufacturer workspace.
00:25
And the first thing that I want to do is change the units in this case.
00:28
What we're going to be doing is we're going to be creating a tool library.
00:31
Infusion 3 60. The tool library is going to be independent of any document.
00:35
So changing the units here isn't really needed.
00:38
However,
00:39
it will affect the units that we see displayed
00:41
at the very basic level in our tool library.
00:44
Note that inside of our tool library there's going to be an all section
00:48
will be documents which will be tools that are used in your current document.
00:51
If you have multiple setups,
00:53
you'll also see them listed here underneath your untitled document.
00:57
We have a cloud library, a local library, the fusion 3 60 samples.
01:01
And at the very bottom we can download vendor libraries.
01:04
It's important to note that if you right click on the library,
01:08
you have the ability to turn the libraries on and off.
01:11
This can be done for individual samples.
01:14
For example, if you're not using any of the metric holders,
01:17
you can right click and you can turn this library off.
01:20
This means that it won't be displayed when you're taking a look at the
01:23
various tools and filtering through the different
01:26
holders inside of the sample library.
01:28
If you want to bring it back, you can always right click and turn that library on.
01:32
We're not going to be going through our vendor libraries in this case,
01:35
but I do think that it's important to explore what tools you
01:38
can download from vendor libraries without having to set them up manually.
01:42
Also note that if you don't see cloud listed inside of your tool library,
01:46
make sure that you go to your user preferences and
01:49
we want to make sure that we do enable them
01:51
from the general section you want to go to manufacture
01:53
and make sure that enable cloud libraries is checked.
01:57
Now let's go back into our tool library and let's take
01:60
a look at how we can create our own library.
02:02
All the tools inside of the fusion 3 60 sample library are read only.
02:07
This means that we can take a look at them and we
02:08
can use them in the current document but we can't modify them.
02:12
What we can do is we can create a library in either our local or our cloud location.
02:17
If you happen to log into fusion 360 from multiple computers.
02:20
It's a good idea that you do use the cloud location.
02:23
There are other places in which you can save
02:25
two libraries as well as post processor data by using
02:28
the assets inside of the data panel but we're going
02:31
to focus solely on the cloud and local libraries.
02:34
We're gonna right click and we can either create
02:36
a new empty library that we want to populate.
02:39
We can create a new folder inside of our cloud library or we can import a library.
02:43
I'm gonna select import and navigate to the three axis
02:46
sample library dot tools that we have with the course.
02:50
Once we select okay notice that now inside of our three access sample library,
02:54
we have a cat 40
03:02
If we expand the cloud library, you can see that three access sample is listed here.
03:06
This sample library only contains this one tool and this holder,
03:10
it's always a good idea that we double check our filters to
03:12
make sure that we don't have any of our filters turned on.
03:15
For example, if you enable milling, you can see that the holder is no longer visible.
03:19
So we want to make sure that any filters
03:21
are cleared and note that we only have our quarter
03:23
end mill and the holder
03:25
in order to create new tools,
03:27
we can either create them from scratch or you can bring them
03:29
in from the fusion 3 60 library or a downloaded vendor library.
03:33
I'm gonna begin by going to the Fusion 3 60 library.
03:37
I'm gonna begin filtering by milling.
03:39
I want to take a look at flat end mills and then I
03:42
want to look for the animals that I need for my specific size.
03:45
In this case we're going to be using a half inch flat and a three quarter flat.
03:50
So as I look through this list, I've got a half inch flat end mill.
03:53
When I select it, notice that there are cutting data presets.
03:57
We have ones for aluminum slotting, roughing and finishing.
04:01
This data is important to review because it doesn't necessarily fit with
04:05
your specific machine or the tool that you're going to use.
04:08
Remember that these are generic tools and their unspecified
04:11
materials and they don't have vendor product links.
04:14
So make sure that you do identify the speeds and
04:17
feeds that you do need to use with these tools.
04:19
But what we're going to do is we're going to
04:21
right click on this tool and select copy tool.
04:25
Go back into our three access sample and we're going to right click and paste
04:29
once again when we do this,
04:31
it's important that we note the filters are going to be active
04:34
and we should clear any filters so we can't see our holder.
04:37
When we take a look at this half inch flat end mill.
04:40
Notice that it doesn't have a tool number
04:43
tool number five is a quarter inch flat end mill.
04:45
Now,
04:46
what we want to do is we want to make sure that
04:47
we edit the properties by right clicking and editing the tool.
04:51
We're going to leave the quarter inch flat end mill as tool number five
04:55
and in the post processor section for our half inch flat end mill.
04:59
We're going to set this at tool number six.
05:02
When we do that,
05:03
the length offset and diameter offset automatically update to six as well.
05:07
It's also important that we take a look at our cutter
05:09
data notice that it's listed as a three flute tool.
05:12
It's going to be using the inch
05:14
unit system and currently the material is unspecified
05:18
if we're using a specific tool such as a car by tool. It's a good idea to specify
05:22
that,
05:23
make sure that the number of flutes is going to match because all
05:26
of these things will affect the overall and use of the tool.
05:30
The diameter is correct at half inch. The overall length at three inch.
05:34
The length below holder is the amount it's sticking out
05:36
below our holder and the shoulder length is one inch.
05:39
This all matches data that we're going to be using
05:42
when we go to the holder section. Notice that by default it's using this cat 40 E. R. 32
05:50
What we can do is we can remove the holder and we can pick a different holder.
05:54
If we have one
05:55
again,
05:56
you can take a look in the three axis samples
05:57
and make sure that you do have the correct holder
05:60
if you want to reassign a holder. What we can do is remove the holder from this,
06:04
we can select and use this holder in its place.
06:07
It's always a good idea to double check the cutting data
06:09
to make sure your length below holder is still the same
06:12
at this point we're going to go ahead and accept this and
06:15
now we've got tool number six are half inch flat end mill.
06:18
We also want to make sure that we have a three quarter flat end mill.
06:21
This is going to be used for us to face and machine the top of our part for this.
06:26
I'm gonna go ahead and hit plus to create a new tool.
06:29
I'm going to select flat end mill and I'm going to
06:32
give it a description of three quarter inch flat end mill
06:37
for the cutter. I'm going to make sure that it is a three flute high speed steel.
06:41
The diameter is going to be 30.75,
06:44
which is going to automatically update the shaft diameter,
06:47
the overall length of three inches, the length below holder of 1.1.
06:51
The shoulder length is going to be one inch and the
06:54
flute length we're going to set as one inch as well
06:58
For the holder. Once again, we want to use that same cap 40.
07:01
It's not strictly required that we are using a holder inside of our tool definition,
07:06
but it is important when we come down to programming our tool paths,
07:10
we want to make sure that the non cutting portion of the tool and
07:13
the holder itself doesn't collide with one machine stock or any of our fixtures.
07:18
I'm gonna set this at tool number four and I'm going to select accept.
07:22
Now we have the tools for our machining or milling applications.
07:26
We want to create the spot drill, the finish drill and the taps as well for that.
07:30
I'm going to go back into my samples.
07:32
I'm going to start looking at whole making category and I want to find a drill bit,
07:37
a spot drill and a tap.
07:38
So I'm going to begin with the spot drill and
07:40
I'm going to find an eighth inch spot drill,
07:42
right click copy tool.
07:44
Go back to my sample, right click and paste the tool.
07:48
Once again,
07:49
the filters are active so you're only going to be seeing the whole making tools.
07:53
Now I want to change from a spot drill to a drill bit.
07:56
We're going to be looking for a 0.201.
07:59
As we scroll down through here,
08:00
we want to make sure that we find the correct
08:02
tool that's going to be used to drill this hole.
08:04
This is the number seven.
08:06
We're going to go ahead and right click and copy this tool and in
08:10
our three access sample we're going to right click and paste the tool.
08:14
The last thing that we are going to need is going to be a right hand tap.
08:18
This is going to be a quarter 20 tap.
08:19
So we want to look through our list, find a quarter 20 tap, right click and copy it.
08:25
Also note that we are able to drag and drop into the three access sample.
08:28
And what that does is it will create a copy of it for us as well.
08:32
This can prevent you from going back and forth
08:34
between the samples and into our current cloud library.
08:38
Once again, make sure that we deactivate the filters.
08:40
We want to assign tool numbers to all these tools,
08:43
I'm going to edit the eighth inch spot drill.
08:46
Go to post process and set this at tool number one.
08:50
We're going to accept that we're going to go to our number seven drill,
08:54
we're going to edit the tool.
08:55
I'm going to set this as tool number two
08:58
and last. I want to go into my quarter 20 tap.
09:02
I'm going to edit the tool and set this as tool number three.
09:06
The tools don't need to be in numerical order.
09:08
They simply need to match however you have them set up inside of your machine.
09:13
It's important to note that the spot drill,
09:15
the drill bit and the quarter 20 tap all have varying levels of detail.
09:20
The tap doesn't contain a holder but the drill and
09:23
the spot drill are using a 40 taper drill chuck.
09:27
So again, it's important to note,
09:28
we want to make sure that these tools can go all the
09:32
way down Down to the bottom of whatever we're machining or drilling.
09:35
Make sure that you validate the speeds and speeds
09:37
that are going to be used in this case.
09:40
Note that in this spot drill,
09:42
the aluminum finishing has a 12,000 rpm
09:45
spindle speed.
09:46
That's going to be too fast for the machine that we're likely going to use.
09:49
And that's something that we would need to adjust.
09:51
This can be done by right clicking and editing the tool.
09:55
We can go to its cutting data,
09:57
make sure that we're on aluminum finishing and we can reduce this value to 8100,
10:02
which should be our limit when we do that.
10:04
It's going to update our surface speed as well as our feed per tooth values.
10:08
The fx next to it is going to tell us that is linked to a parameter
10:12
and those parameters are going to be adjusted
10:15
based on changing just our spindle speed.
10:17
We're going to accept that change and then we're going to close our tool library
10:21
because the tool libraries are saved in the cloud or locally,
10:24
there is no safe option that we need to do.
10:26
Remember that they are independent of our design.
10:29
So the untitled document does not need to be saved
10:32
at this point.
10:33
If you want to make any changes to the tool library,
10:35
go ahead before moving on to the next step
After completing this video, you will be able to:
Step-by-step guide
