Define a digital CNC setup

00:02

define a digital CNC setup.

00:06

After completing this video, you'll be able to

00:09

define a digital CNC machine, create stock,

00:12

select a box point to locate a world coordinate system

00:15

and define a coordinate system reference

00:20

Infusion 3 60. We'll take a look at the supply data set mounting block dot F three D.

00:25

We're going to be creating a cam setup which allows

00:28

us to create tool past the machine are part.

00:31

The first thing that we want to do is navigate to the

00:33

manufacturer workspace and before getting started

00:36

double check the units by default.

00:38

The units will be set to millimeters but we're going to reset

00:40

ours two inch if you want to use inch every time.

00:43

You can also toggle it on as default here.

00:47

Once we have our unit set 2",

00:48

we want to make sure that we understand how we can create

00:51

a camp set up and what data is associated with that.

00:54

The camp set up is going to contain all

00:56

the operations for a single position on a machine.

01:00

In this case, if we're dealing with 2.5 or three axis machining,

01:03

this will be a stationary position mounted to the machine.

01:06

If you're dealing with multi axis machines such as fourth or fifth axis machines,

01:10

that becomes a little bit different.

01:12

But in this case we're going to assume our part is fixed on a table. In advice

01:17

from our setup menu, we're going to select the option for new setup

01:20

because we're on the milling tab by default.

01:23

The machine operation type is going to be set to milling

01:26

but it's always a good idea to double check this

01:29

at the very top. We have an optional setting for a machine.

01:33

Machines can contain information that will help us ensure that

01:36

we're creating accurate tool path representation of our physical machine.

01:41

This can be data such as the size of our table.

01:44

The weight limits the number of tools, the amount of movement,

01:48

the table has an X and Y.

01:49

And the amount of travel the spindle has in the Z direction.

01:53

Machine selections can also be used for things like machine simulation where we can

01:58

validate our tool pass while the part is moving on a simulated machine.

02:02

It's important to note that we are going to go through some

02:04

of the machine setting options but we're not going to be using it

02:07

for our simulation.

02:09

When we take a look at our setup,

02:10

we have three tabs by default set up stock and post process.

02:15

Once we select a machine, 1/4 option will appear.

02:19

The first thing that we want to do is go into our fusion 360

02:22

library and then we want to take a look at milling as our capability.

02:26

We can filter by a specific vendor and I'm going to choose hoss at the very top

02:30

and note that we have several different

02:32

machines to select from.

02:34

There is also an option for simulation ready.

02:37

When we select a simulation ready machine this is going to

02:41

have this three D box icon to the right hand side.

02:44

This means that there is a three D model associated with

02:46

it and that three D model is going to be downloaded.

02:49

When we take a look through here, we can find a machine that's going to work for us.

02:53

We've got plenty of multi axis machines. And then here you can see that we have a

02:57

VF one.

02:58

We're going to select the Haas VF one machine

03:01

and notice that it wants us to download the model.

03:04

When we select, download,

03:05

it will bring on the entire model and ask us where we want to save it.

03:09

We're going to save that in the same location of the data set that we're working on.

03:14

Once we have the machine selected and the model downloaded,

03:17

it's going to place our part inside of that machine.

03:22

As we take a look at this,

03:23

you also note that we now have this fourth

03:25

option of part position listed inside of our setup.

03:28

We can always de select the machine or change the machine at any time.

03:32

But for right now let's leave the

03:33

VF one

03:34

again,

03:35

The operation type is milling and next

03:36

we want to change the coordinate system orientation

03:39

by default, you can see that Z is pointing away from the part,

03:43

we want to make sure that Z is pointing up,

03:45

We're going to select the Z axis plane option.

03:48

And then for our Z axis we want to select the default. Y.

03:52

This is going to put Z in the correct orientation and now

03:54

we have X pointing to the right and why pointing away.

03:57

In this case we don't have advice or a fixture holding our part.

04:01

So we're going to pass the fixture option.

04:04

But it is always important that we do select those,

04:06

especially if we're going to be machining relatively close

04:09

as we can use them for collision checking.

04:12

Next we want to go to our stock section.

04:14

A stock section is going to be based on our part

04:17

as a relative size with stock offset in various directions.

04:21

In most cases you might have a solid body that represents the stock,

04:25

in which case you can change this to from solid.

04:28

If you're working on a second or multiple operations you can

04:31

use from proceeding set up and carry on with rest machining.

04:35

In this case I'm going to use a fixed size box and I

04:38

want to make sure that the fixed size box is going to be

04:41

the correct whip notice that there are round up options to the nearest

04:45

half inch and we're using a three by 1.5 by one inch stock,

04:50

we can see that the model dimensions are 2.875 by 1.375 by 0.6875.

04:58

Now that we have our stock defined,

04:60

I'm going to move back into the first half of our setup,

05:02

I wanted to find the coordinate system location.

05:05

I'm going to be using the stock point option and placing it at the back left corner,

05:10

this is going to be a typical location in addition to the top center of our part.

05:15

Typically the back left corner is used on first operations,

05:18

especially when you're using something like an edge finder and a stop on your vice.

05:22

However, if using probing to find the location of your center,

05:25

oftentimes you'll be using the sides of the part and

05:28

probing will find the center location of your stock.

05:32

The part position is going to determine where our part is located on the machine.

05:36

You can see as we zoom away that the part is located right now in

05:40

the middle of the machine because we don't have a vice on the part.

05:43

You can see that it's going to be directly on the table.

05:45

So I'm going to move it up a distance of 2.5 inches which should stimulate the height.

05:50

It's going to be inside of our vice.

05:52

Next I'm going to move to post process.

05:55

This is where we're going to determine our program number

05:57

and we're also going to add a program Comet.

06:00

I'm gonna use 10011 as my program number and comment. I'm going to put certain prep

06:09

from our machine WCS because we have a machine selected.

06:13

It's going to show a format a standard or extended and the

06:17

WCS is going to represent G 54 on this Haas VF one.

06:22

If we were to de select our machine. The WCS asset numbers would be 0123 and so on.

06:28

Zero and one, both representing G 54.

06:32

We also have an option to use multiple wCS offsets.

06:35

This will allow us to use multiple offsets of the same program.

06:39

For example, if we choose multiple offsets, increments of one

06:43

number of instances three,

06:45

we would be posting the same code to G 54 G 55

06:49

G 56.

06:51

This is helpful if you're creating a production run for

06:53

your parts with multiple work stations on a machine.

06:55

However, for our example, we're going to leave it at G 54

06:59

say, okay

07:01

now we have our setup created and if we zoom out we

07:03

can see that we have the entire Haas VF one machine.

07:06

When we view this from the front,

07:08

the part is located inside of the cabinet with the doors open and we can

07:12

see everything in terms of the tool holder setup and the location of our part.

07:17

If you want to hide the machine,

07:18

you can always expand the setup and note that there is an eye icon next to the

07:22

V. F one.

07:23

This will allow us to hide the machine and only show our

07:25

part and setup when setup is selected will get a preview of

07:29

the stock as well as the WCS location on the screen as

07:32

soon as we left click in the canvas area and set up.

07:35

One is DE selected. You'll note that now the stock preview is gone.

07:39

We can also rename our set ups and tool paths.

07:42

At any point in time, I'm going to call this O. P. One for operation one

07:47

At this point, let's make sure that we do save the design before moving on.