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Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
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Professional CAD/CAM tools built on Inventor and AutoCAD
Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
Professional CAD/CAM tools built on Inventor and AutoCAD
Transcript
00:02
Create a 3D model from a blueprint
00:07
in this video.
00:08
We'll review a blueprint,
00:09
create sketches and features to reproduce a design and will verify a design
00:16
Infusion 3 60. We're going to get started taking a look at engine case R.
00:20
H no timeline and engine assembly intro to cad CAm C and C.
00:25
We're going to be modeling the engine case, right hand component.
00:29
So I wanted to make sure that we provided it in the context
00:32
of its assembly as well as its own part with no timeline.
00:36
So the assembly has a rotating crank and it allows you to move a piston up and down.
00:42
We're going to be focusing on just a single component of this assembly
00:46
and we want to make sure that we identify
00:48
the different features that are going to be critical.
00:50
So the first thing that we need to do is we need to take a look at
00:54
a blueprint so we can understand all the dimensions
00:57
we need to measure and create this part.
00:59
So let's go ahead and open up that blueprint.
01:03
So make sure that you have the engine case. R. H drawing E N G 1008 open.
01:09
This is a single sheet blueprint that gives
01:11
us information about things like the material,
01:14
the tolerance values as well as all of the
01:17
dimensions that we need to create this part.
01:20
Now there are going to be a handful of things that we
01:22
need to understand and we've already looked at a couple different blueprints.
01:26
So first let's take a quick look at this and then we'll jump in to start modeling.
01:31
If we take a look at the overall dimensions of the part,
01:33
this is going to be a great place for us to start.
01:36
This is essentially a block that has
01:38
some rounded corners and some internal features.
01:40
So we need to take a look at the overall dimensions 2.375 by 1.4 by 0.938.
01:49
Notice that these do not have dimensions applied so they fall into
01:52
the dimensions and tolerances based on the number of decimal places.
01:57
So we're going to be using these values to
01:59
get started creating the outside shape of our part.
02:02
We can see that there's a radius value here for that outside corner
02:06
and then we also have positions of the threaded holes.
02:10
We also know that there are 1032 going down .375 or 3/8s.
02:15
We can see that we've got information about the depth
02:17
of the pocket on the inside its radius value.
02:22
We know that these two edges are a certain distance apart based on this view here.
02:31
So if you have multiple screens,
02:34
I suggest that you keep this visible on your other monitor so that you can
02:38
take a look at it while we're modeling if you don't have that available option.
02:42
Another thing that you can do is take a screenshot of this as a jpeg
02:47
or a PNG and you can insert it into fusion 3 60 as a graphic.
02:52
I'll show you how to do that.
02:53
But for our example we're going to be taking a look at using it on a second screen.
02:57
So we want to begin by starting a new design and instead of the
03:01
new design because all of the units on the detailed drawing are inches.
03:05
We want to make sure that we set our unit type two inch.
03:07
We're going to go to insert,
03:10
we're going to select canvas and then we need to pick the canvas image.
03:14
So with the data sets provided there is an image
03:17
file of the detailed drawing as well as the pdf.
03:21
You want to make sure you navigate to the location. You saved your data sets.
03:25
You want to select the image file and you want to select the plane to place it on.
03:29
In this case I'm going to be using the front plane,
03:33
I'm going to look at this from the front and I'm going to say,
03:35
Okay now the trick with this is you want to make sure that it's appropriately scaled.
03:40
It doesn't necessarily have to be scaled but we can select the image
03:44
right click and calibrate and notice that the image is actually backwards.
03:48
But I'm going to select one of the dimensions here and I'm going to set this to 2.13,
03:53
that's the dimension in there
03:56
and then I want to edit the canvas one more time and I'm going to flip it horizontally.
04:02
Another thing that you want to be mindful of is the location of your origin.
04:05
This can be pretty confusing if the canvases directly behind you so we
04:09
can right click edit and just simply move it out of our way.
04:13
I'm gonna go ahead and place it off to the left hand side and say, okay,
04:17
so if you want to you can use this as your reference.
04:19
I think it's a lot easier to have it on a second monitor or printed out if possible.
04:24
So if you have that option then make sure that you do that.
04:28
If you have to have it on the single screen,
04:30
then you can insert it as a canvas again for us.
04:33
I'm going to be hiding that because it just adds
04:35
a little bit too much confusion to the screen.
04:37
Now that we're ready to start modeling,
04:39
I'm going to hide my origin and I'm going to begin creating a sketch.
04:43
I'm going to use the same front plane and I'm going to use my rectangle tool
04:47
inside of the sketch palette.
04:49
I want to select the option for a center rectangle because I
04:51
want to center it about the origin and begin dragging this out.
04:55
The overall size of our part is 2.375 x 1.4".
05:02
I'm going to finish that sketch. I'm going to rotate this around slightly
05:06
and I want to extrude this.
05:09
I want to make sure that I am centered about the origin.
05:11
So I'm going to use symmetric with the whole length set
05:14
for my measurement and this is going to be .938.
05:19
This is going to give me the base block size for the engine case.
05:24
Next I'm going to add the, fill it to that outside corner.
05:27
I'm going to select my Philip tool.
05:29
I'm going to grab both of these and on the detailed drawing, the radius of that is .25.
05:34
It is important that we remember we are entering a radius value and not a diameter.
05:39
So we do want to enter .25.
05:41
If your detailed drawing happens to list a diameter value, you do want to be careful.
05:47
The next thing that we want to do is we want to think about any other features.
05:51
So we've got tapped holes on the top and we've also got internal features.
05:55
I'm going to start creating the tapped holes on the top by selecting the face,
05:59
right clicking and creating a sketch.
06:02
I'm gonna go to create
06:04
select point
06:06
And I'm going to place two points.
06:08
Then I want to use my dimension tool again referencing the detailed drawing.
06:13
And I'm going to add a detailed dimension of .688
06:18
And then I also want to add a dimension of .25 from the left edge.
06:24
And I have a dimension of 2.125 from that same left edge to that next point.
06:31
Now this can be tricky,
06:32
especially once you have a dimension here because
06:35
sometimes it will want to select that dimension.
06:37
You might want to select a corner point or de select the dimension first.
06:42
In this case, I'm going to say 2.125.
06:46
Now the vertical height of this is going to be the same.
06:49
It's referenced on the drawing as a single dimension.
06:52
But sometimes we have to make these inferences based
06:55
on the way that the details laid out.
06:57
We could either add another dimension or we can use our horizontal constraint
07:02
to set both of these points horizontally.
07:05
We're going to finish the sketch and then we're going
07:07
to go to our create and select the whole tool.
07:10
When we use the whole tool, we have a placement option from sketch.
07:15
When we use from sketch, we can select each of these points.
07:18
Then we need to determine what the whole type is going to be.
07:21
We're going to set this one equal to a simple hole, it's going to be tapped.
07:27
And the distance value that we're going to be
07:29
using is going to be based on the drawing.
07:32
And that's a 1032 hole that goes down .375. So the depth instead of 1" will be .375.
07:40
And because we're doing a tapped hole, we're going to select the size.
07:44
And as we scroll, you can see that a number 10 is listed here
07:47
and we'll pick a 1032 because this is a fine thread
07:51
we can select the class.
07:53
If it happens to be listed on the drawing in this case it's not.
07:56
So I'm going to use the tightest option of to be and say, okay
08:00
now we've got the tapped holes on the top, we can move over to the next face.
08:05
Looking at the detailed drawing once more,
08:07
I can see that I want to remove material from this face.
08:11
So I'm going to start by creating a sketch here.
08:14
The center of this has a boar and it's not centered
08:17
about the origin or at least from the detailed drawing.
08:20
We don't know if it's exactly centered.
08:22
So instead of placing it at the origin,
08:24
I'm going to place it just slightly below and I'm going to place three circles here.
08:30
The reason that we want to do three circles is because we've got the center bore.
08:34
But then we also have the larger cutout section.
08:37
Let's start with our sketch dimensions on the inside bore.
08:41
This is going to be a diameter value and we can see based on the dimension leaders
08:46
this diameter is going to be .438.
08:50
The diameter of the next one is going to be .69
08:54
and this large one is listed as a radius value.
08:58
So if we right click, we're able to change this to a radius value.
09:02
So this way we don't have to do
09:04
any mathematical operators in the dimension dialogue,
09:07
we can hit .69 as the radius value.
09:10
All three of these were sketched concentric,
09:13
so if we hit escape to get off our dimension tool,
09:15
we can drag them all up and down together.
09:18
Notice that they can also move left and right.
09:20
We know that we want them to be symmetric on
09:23
the design but there is a dimension for that.
09:26
So let's go ahead and apply it
09:27
from the left hand side to the center point of all of these. We have 1.188.
09:35
Then we have a distance from the top edge.
09:39
So if we take a look again at the detailed drawing, this is an important aspect.
09:43
We want to make sure we understand the location of these features.
09:48
The distance for the center of this location comes from section B. B.
09:52
The section view is showing the center at 0.625.
09:57
So this gives us the position of the boss that's
09:60
in the center but also this larger cut out.
10:02
We do have some vertical edges to create the rest of this cut out.
10:06
So I'm going to use the line tool and draw some vertical lines that snap
10:10
to this edge and we're going to go ahead and draw one up over here.
10:14
I'm going to use the tangent option to make sure that these are tangent
10:19
And then I'm going to use my dimension tool. A dimension is given at 1.38.
10:24
So I want to figure out what the distances between these two.
10:27
Fusion tells us that this will over define our sketch, but we're going to say, okay,
10:32
and have it display a driven dimension.
10:35
We want to make sure that the driven dimension matches
10:38
the dimension on the detailed drawing because they do match.
10:41
I'm going to leave this here as a reference but note that our vertical edges that are
10:45
perpendicular with the top and tangent with this
10:48
larger diameter circle gives us the exact dimension.
10:52
So sometimes we have to infer that from the detailed drawing.
10:56
Let's go ahead and finish this sketch and let's create some extra roots.
11:00
We're going to use the extrude tool and
11:02
I'm going to extrude these three larger sections.
11:06
And as we begin dragging this back,
11:08
you can see that we are removing material however,
11:11
we need to think about the distance that this
11:13
goes back and based on the detailed drawing,
11:16
we're going to go -188 and we can see that from our top view.
11:31
Next we need to remove the material from the inside.
11:34
So we'll have to go into our sketches, show sketch three and select that inside boss.
11:39
We use extrude and this time we're going
11:42
to select the distance option of through all.
11:46
Lastly, we need to get this boss height in the right position,
11:49
so I'm going to select that boss face.
11:51
We're going to select extrude, begin pulling it back and this is going to be -1531.
11:59
Now that we have those features, we can go ahead and we can hide that sketch.
12:03
There is a handful of other features that need to be created on this design,
12:07
but this is a great time for us to save because we've made a lot of progress.
12:11
Let's go ahead and make sure that we save this design as engine case. R. H.
12:17
For right hand and hit enter once your design is saved,
12:21
let's go ahead and move on to the next step.
Video transcript
00:02
Create a 3D model from a blueprint
00:07
in this video.
00:08
We'll review a blueprint,
00:09
create sketches and features to reproduce a design and will verify a design
00:16
Infusion 3 60. We're going to get started taking a look at engine case R.
00:20
H no timeline and engine assembly intro to cad CAm C and C.
00:25
We're going to be modeling the engine case, right hand component.
00:29
So I wanted to make sure that we provided it in the context
00:32
of its assembly as well as its own part with no timeline.
00:36
So the assembly has a rotating crank and it allows you to move a piston up and down.
00:42
We're going to be focusing on just a single component of this assembly
00:46
and we want to make sure that we identify
00:48
the different features that are going to be critical.
00:50
So the first thing that we need to do is we need to take a look at
00:54
a blueprint so we can understand all the dimensions
00:57
we need to measure and create this part.
00:59
So let's go ahead and open up that blueprint.
01:03
So make sure that you have the engine case. R. H drawing E N G 1008 open.
01:09
This is a single sheet blueprint that gives
01:11
us information about things like the material,
01:14
the tolerance values as well as all of the
01:17
dimensions that we need to create this part.
01:20
Now there are going to be a handful of things that we
01:22
need to understand and we've already looked at a couple different blueprints.
01:26
So first let's take a quick look at this and then we'll jump in to start modeling.
01:31
If we take a look at the overall dimensions of the part,
01:33
this is going to be a great place for us to start.
01:36
This is essentially a block that has
01:38
some rounded corners and some internal features.
01:40
So we need to take a look at the overall dimensions 2.375 by 1.4 by 0.938.
01:49
Notice that these do not have dimensions applied so they fall into
01:52
the dimensions and tolerances based on the number of decimal places.
01:57
So we're going to be using these values to
01:59
get started creating the outside shape of our part.
02:02
We can see that there's a radius value here for that outside corner
02:06
and then we also have positions of the threaded holes.
02:10
We also know that there are 1032 going down .375 or 3/8s.
02:15
We can see that we've got information about the depth
02:17
of the pocket on the inside its radius value.
02:22
We know that these two edges are a certain distance apart based on this view here.
02:31
So if you have multiple screens,
02:34
I suggest that you keep this visible on your other monitor so that you can
02:38
take a look at it while we're modeling if you don't have that available option.
02:42
Another thing that you can do is take a screenshot of this as a jpeg
02:47
or a PNG and you can insert it into fusion 3 60 as a graphic.
02:52
I'll show you how to do that.
02:53
But for our example we're going to be taking a look at using it on a second screen.
02:57
So we want to begin by starting a new design and instead of the
03:01
new design because all of the units on the detailed drawing are inches.
03:05
We want to make sure that we set our unit type two inch.
03:07
We're going to go to insert,
03:10
we're going to select canvas and then we need to pick the canvas image.
03:14
So with the data sets provided there is an image
03:17
file of the detailed drawing as well as the pdf.
03:21
You want to make sure you navigate to the location. You saved your data sets.
03:25
You want to select the image file and you want to select the plane to place it on.
03:29
In this case I'm going to be using the front plane,
03:33
I'm going to look at this from the front and I'm going to say,
03:35
Okay now the trick with this is you want to make sure that it's appropriately scaled.
03:40
It doesn't necessarily have to be scaled but we can select the image
03:44
right click and calibrate and notice that the image is actually backwards.
03:48
But I'm going to select one of the dimensions here and I'm going to set this to 2.13,
03:53
that's the dimension in there
03:56
and then I want to edit the canvas one more time and I'm going to flip it horizontally.
04:02
Another thing that you want to be mindful of is the location of your origin.
04:05
This can be pretty confusing if the canvases directly behind you so we
04:09
can right click edit and just simply move it out of our way.
04:13
I'm gonna go ahead and place it off to the left hand side and say, okay,
04:17
so if you want to you can use this as your reference.
04:19
I think it's a lot easier to have it on a second monitor or printed out if possible.
04:24
So if you have that option then make sure that you do that.
04:28
If you have to have it on the single screen,
04:30
then you can insert it as a canvas again for us.
04:33
I'm going to be hiding that because it just adds
04:35
a little bit too much confusion to the screen.
04:37
Now that we're ready to start modeling,
04:39
I'm going to hide my origin and I'm going to begin creating a sketch.
04:43
I'm going to use the same front plane and I'm going to use my rectangle tool
04:47
inside of the sketch palette.
04:49
I want to select the option for a center rectangle because I
04:51
want to center it about the origin and begin dragging this out.
04:55
The overall size of our part is 2.375 x 1.4".
05:02
I'm going to finish that sketch. I'm going to rotate this around slightly
05:06
and I want to extrude this.
05:09
I want to make sure that I am centered about the origin.
05:11
So I'm going to use symmetric with the whole length set
05:14
for my measurement and this is going to be .938.
05:19
This is going to give me the base block size for the engine case.
05:24
Next I'm going to add the, fill it to that outside corner.
05:27
I'm going to select my Philip tool.
05:29
I'm going to grab both of these and on the detailed drawing, the radius of that is .25.
05:34
It is important that we remember we are entering a radius value and not a diameter.
05:39
So we do want to enter .25.
05:41
If your detailed drawing happens to list a diameter value, you do want to be careful.
05:47
The next thing that we want to do is we want to think about any other features.
05:51
So we've got tapped holes on the top and we've also got internal features.
05:55
I'm going to start creating the tapped holes on the top by selecting the face,
05:59
right clicking and creating a sketch.
06:02
I'm gonna go to create
06:04
select point
06:06
And I'm going to place two points.
06:08
Then I want to use my dimension tool again referencing the detailed drawing.
06:13
And I'm going to add a detailed dimension of .688
06:18
And then I also want to add a dimension of .25 from the left edge.
06:24
And I have a dimension of 2.125 from that same left edge to that next point.
06:31
Now this can be tricky,
06:32
especially once you have a dimension here because
06:35
sometimes it will want to select that dimension.
06:37
You might want to select a corner point or de select the dimension first.
06:42
In this case, I'm going to say 2.125.
06:46
Now the vertical height of this is going to be the same.
06:49
It's referenced on the drawing as a single dimension.
06:52
But sometimes we have to make these inferences based
06:55
on the way that the details laid out.
06:57
We could either add another dimension or we can use our horizontal constraint
07:02
to set both of these points horizontally.
07:05
We're going to finish the sketch and then we're going
07:07
to go to our create and select the whole tool.
07:10
When we use the whole tool, we have a placement option from sketch.
07:15
When we use from sketch, we can select each of these points.
07:18
Then we need to determine what the whole type is going to be.
07:21
We're going to set this one equal to a simple hole, it's going to be tapped.
07:27
And the distance value that we're going to be
07:29
using is going to be based on the drawing.
07:32
And that's a 1032 hole that goes down .375. So the depth instead of 1" will be .375.
07:40
And because we're doing a tapped hole, we're going to select the size.
07:44
And as we scroll, you can see that a number 10 is listed here
07:47
and we'll pick a 1032 because this is a fine thread
07:51
we can select the class.
07:53
If it happens to be listed on the drawing in this case it's not.
07:56
So I'm going to use the tightest option of to be and say, okay
08:00
now we've got the tapped holes on the top, we can move over to the next face.
08:05
Looking at the detailed drawing once more,
08:07
I can see that I want to remove material from this face.
08:11
So I'm going to start by creating a sketch here.
08:14
The center of this has a boar and it's not centered
08:17
about the origin or at least from the detailed drawing.
08:20
We don't know if it's exactly centered.
08:22
So instead of placing it at the origin,
08:24
I'm going to place it just slightly below and I'm going to place three circles here.
08:30
The reason that we want to do three circles is because we've got the center bore.
08:34
But then we also have the larger cutout section.
08:37
Let's start with our sketch dimensions on the inside bore.
08:41
This is going to be a diameter value and we can see based on the dimension leaders
08:46
this diameter is going to be .438.
08:50
The diameter of the next one is going to be .69
08:54
and this large one is listed as a radius value.
08:58
So if we right click, we're able to change this to a radius value.
09:02
So this way we don't have to do
09:04
any mathematical operators in the dimension dialogue,
09:07
we can hit .69 as the radius value.
09:10
All three of these were sketched concentric,
09:13
so if we hit escape to get off our dimension tool,
09:15
we can drag them all up and down together.
09:18
Notice that they can also move left and right.
09:20
We know that we want them to be symmetric on
09:23
the design but there is a dimension for that.
09:26
So let's go ahead and apply it
09:27
from the left hand side to the center point of all of these. We have 1.188.
09:35
Then we have a distance from the top edge.
09:39
So if we take a look again at the detailed drawing, this is an important aspect.
09:43
We want to make sure we understand the location of these features.
09:48
The distance for the center of this location comes from section B. B.
09:52
The section view is showing the center at 0.625.
09:57
So this gives us the position of the boss that's
09:60
in the center but also this larger cut out.
10:02
We do have some vertical edges to create the rest of this cut out.
10:06
So I'm going to use the line tool and draw some vertical lines that snap
10:10
to this edge and we're going to go ahead and draw one up over here.
10:14
I'm going to use the tangent option to make sure that these are tangent
10:19
And then I'm going to use my dimension tool. A dimension is given at 1.38.
10:24
So I want to figure out what the distances between these two.
10:27
Fusion tells us that this will over define our sketch, but we're going to say, okay,
10:32
and have it display a driven dimension.
10:35
We want to make sure that the driven dimension matches
10:38
the dimension on the detailed drawing because they do match.
10:41
I'm going to leave this here as a reference but note that our vertical edges that are
10:45
perpendicular with the top and tangent with this
10:48
larger diameter circle gives us the exact dimension.
10:52
So sometimes we have to infer that from the detailed drawing.
10:56
Let's go ahead and finish this sketch and let's create some extra roots.
11:00
We're going to use the extrude tool and
11:02
I'm going to extrude these three larger sections.
11:06
And as we begin dragging this back,
11:08
you can see that we are removing material however,
11:11
we need to think about the distance that this
11:13
goes back and based on the detailed drawing,
11:16
we're going to go -188 and we can see that from our top view.
11:31
Next we need to remove the material from the inside.
11:34
So we'll have to go into our sketches, show sketch three and select that inside boss.
11:39
We use extrude and this time we're going
11:42
to select the distance option of through all.
11:46
Lastly, we need to get this boss height in the right position,
11:49
so I'm going to select that boss face.
11:51
We're going to select extrude, begin pulling it back and this is going to be -1531.
11:59
Now that we have those features, we can go ahead and we can hide that sketch.
12:03
There is a handful of other features that need to be created on this design,
12:07
but this is a great time for us to save because we've made a lot of progress.
12:11
Let's go ahead and make sure that we save this design as engine case. R. H.
12:17
For right hand and hit enter once your design is saved,
12:21
let's go ahead and move on to the next step.
Step-by-step guide
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