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Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
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Professional CAD/CAM tools built on Inventor and AutoCAD
Integrated BIM tools, including Revit, AutoCAD, and Civil 3D
Professional CAD/CAM tools built on Inventor and AutoCAD
In this exercise, you'll practice how to create a component, create a sketch with dimensions/constraints, create a sketch projection onto a surface, use Extrude, and create a Rectangular Pattern.
Exercise
Transcript
00:01
This is a practice exercise video solution
00:06
for this practice exercise.
00:07
Let's begin with the supplied data set saw blade dot f three D.
00:11
Currently we have a blade and a blade holder,
00:13
we want to create a new version of this blade.
00:16
So we're going to get started by going to assemble a new component.
00:20
We're going to call this new component,
00:22
new blade.
00:27
Once we have the new blade component, it's time to start sketching.
00:30
We're going to go ahead and hide the blade holder as it's not needed for this example.
00:35
Next we need to decide if we want to project the edges of the current holder
00:39
or if we want to project the entire face by starting a sketch on it.
00:43
Let's take a look at where our origin is.
00:46
You'll notice when we select the origin,
00:47
the plane is way over here and the origin is located
00:50
in space and not necessarily aligned to our saw blade.
00:54
To ensure that everything is designed in place.
00:56
We can either move our coordinate system of this component
00:59
or we can decide to sketch directly on the face.
01:03
I'm going to hide the origin for now and I'm going to activate the top level,
01:07
select my component and I want to use the move option,
01:11
we're going to move the component from and to We
01:14
also have the option to go point to point position.
01:17
We're going to select point to point and we're going to
01:20
again enable our origin selecting our origin point as the from
01:24
and
01:25
the center location of the blade. As to and will capture that location.
01:30
Now when we activate our new blade,
01:32
our coordinate system is now going to be located here,
01:34
which means that we can use one of our default planes to create our new sketch.
01:38
Once again, you could sketch directly on the face of the blade.
01:42
But having the coordinate system in the right location is certainly handy.
01:46
What we're going to do now is create a new sketch, selecting our plane.
01:49
This means that we're not bringing in the reference of the salt,
01:53
but I do want to bring in some geometry.
01:55
So I'm gonna go to project include and project.
01:58
I want to bring in this front section of the saw
02:01
and I'm going to work my way around selecting each individual section of interest.
02:06
I don't want to bring in the saw teeth as I am going to be creating new ones.
02:09
We could also bring in just a critical geometry and re sketch the rest for ourselves.
02:14
But sometimes it's best to reuse some of these design elements.
02:19
I also want to bring in the center hole and say, OK,
02:22
now that we have that information, we can hide the original blade.
02:26
Next I'm gonna start the line tool and I want to create a new saw blade.
02:30
I'm gonna come up at an angle
02:32
and I'm gonna come straight down.
02:35
Then I'm going to use the dimension tool by hitting D on the keyboard
02:38
or by selecting dimension and determine how far apart these are going to be.
02:42
For this example, I'm going to say two.
02:45
I also want to make sure that these endpoints are horizontal with each other.
02:49
This will fully dimension this
02:51
next We need to create a pattern.
02:53
This pattern is going to mean that each of
02:55
these elements need to line up with each other.
02:58
One way that we can do this is we can create that as a feature pattern,
03:02
assuming that we close off the blade.
03:04
So once again let's grab the line tool,
03:06
let's close off the bottom of this
03:08
and then let's select the endpoint
03:10
and create a horizontal line coming all the way back.
03:15
Next we want to finish off the blade profile.
03:18
I'm going to use a tangent constraint
03:20
And go ahead and select these two.
03:23
We'll finish the sketch and create a new extrude
03:26
to make sure that we have the correct thickness.
03:27
Let's bring back the original blade. Select extrude,
03:30
grab our profile
03:32
including the salt tooth
03:34
and we can extrude it to the other side. Using to object
03:39
this is going to be a new body inside of our current component.
03:43
Once again, we can hide the blade,
03:45
expand our sketches
03:47
and we can hide our origin.
03:49
Next we want to extrude out our saw blade
03:52
so we're going to go ahead and turn this
03:54
around and make sure that we extrude through all.
03:58
Now that we have this feature. We can go ahead and hide the sketch.
04:01
Go to our linear or rectangular pattern
04:04
and select the option to pattern a feature.
04:07
This will be our second extrude.
04:08
Cut the direction will be along the edge of the blade.
04:12
We're going to use a spacing option,
04:14
giving it a two millimeter spacing and that
04:17
should perfectly line up each of the teeth.
04:19
We now just need to increase the number and we can do that
04:22
by grabbing on this manipulator and dragging it toward the plus direction.
04:27
We can also manually increment this,
04:29
giving it a number of teeth that we think is correct.
04:32
In this case let's try 55 and see how close we get.
04:35
You can see that we still need a few more. So let's increase this to 65
04:39
looks like we have one too many. So we'll go down to 64,
04:43
we're going to say, okay,
04:45
and now we've created a new version of the saw blade with a different tooth pattern.
04:50
If we go back to the top level of the design,
04:52
we can bring back the blade holder and we can see our new version of the saw blade.
04:56
We can also hide our new blade and show the old blade with smaller teeth.
05:01
If we make any mistakes, remember that,
05:03
we can always go back and modify our sketches.
05:05
So for example, if we edit this sketch,
05:08
double click the mouse wheel to bring it in view,
05:11
we can determine that this edge does not need
05:13
to be vertical by selecting it and hitting.
05:15
Delete.
05:16
Then we can determine that this edge does not need to be perpendicular.
05:20
This allows us to drag these around.
05:22
We also need to make sure we get rid
05:24
of that perpendicular constraint and make that line horizontal.
05:26
Again.
05:28
We're gonna go ahead and make this front edge vertical,
05:30
and then we'll drag it down until we're at the appropriate angle.
05:34
We can see that two
05:36
is about two of the original teeth and I'm going to dimension this vertical line
05:40
so that it's 1.25 mm.
05:43
Next we'll finish the sketch and all the patterns should update properly.
05:48
Once again,
05:49
we could go back and forth between our new blade and
05:51
the old blade and just see the difference between the two.
05:54
Once we're done with this example,
05:56
let's make sure that we do go back to a front view and save the design.
Video transcript
00:01
This is a practice exercise video solution
00:06
for this practice exercise.
00:07
Let's begin with the supplied data set saw blade dot f three D.
00:11
Currently we have a blade and a blade holder,
00:13
we want to create a new version of this blade.
00:16
So we're going to get started by going to assemble a new component.
00:20
We're going to call this new component,
00:22
new blade.
00:27
Once we have the new blade component, it's time to start sketching.
00:30
We're going to go ahead and hide the blade holder as it's not needed for this example.
00:35
Next we need to decide if we want to project the edges of the current holder
00:39
or if we want to project the entire face by starting a sketch on it.
00:43
Let's take a look at where our origin is.
00:46
You'll notice when we select the origin,
00:47
the plane is way over here and the origin is located
00:50
in space and not necessarily aligned to our saw blade.
00:54
To ensure that everything is designed in place.
00:56
We can either move our coordinate system of this component
00:59
or we can decide to sketch directly on the face.
01:03
I'm going to hide the origin for now and I'm going to activate the top level,
01:07
select my component and I want to use the move option,
01:11
we're going to move the component from and to We
01:14
also have the option to go point to point position.
01:17
We're going to select point to point and we're going to
01:20
again enable our origin selecting our origin point as the from
01:24
and
01:25
the center location of the blade. As to and will capture that location.
01:30
Now when we activate our new blade,
01:32
our coordinate system is now going to be located here,
01:34
which means that we can use one of our default planes to create our new sketch.
01:38
Once again, you could sketch directly on the face of the blade.
01:42
But having the coordinate system in the right location is certainly handy.
01:46
What we're going to do now is create a new sketch, selecting our plane.
01:49
This means that we're not bringing in the reference of the salt,
01:53
but I do want to bring in some geometry.
01:55
So I'm gonna go to project include and project.
01:58
I want to bring in this front section of the saw
02:01
and I'm going to work my way around selecting each individual section of interest.
02:06
I don't want to bring in the saw teeth as I am going to be creating new ones.
02:09
We could also bring in just a critical geometry and re sketch the rest for ourselves.
02:14
But sometimes it's best to reuse some of these design elements.
02:19
I also want to bring in the center hole and say, OK,
02:22
now that we have that information, we can hide the original blade.
02:26
Next I'm gonna start the line tool and I want to create a new saw blade.
02:30
I'm gonna come up at an angle
02:32
and I'm gonna come straight down.
02:35
Then I'm going to use the dimension tool by hitting D on the keyboard
02:38
or by selecting dimension and determine how far apart these are going to be.
02:42
For this example, I'm going to say two.
02:45
I also want to make sure that these endpoints are horizontal with each other.
02:49
This will fully dimension this
02:51
next We need to create a pattern.
02:53
This pattern is going to mean that each of
02:55
these elements need to line up with each other.
02:58
One way that we can do this is we can create that as a feature pattern,
03:02
assuming that we close off the blade.
03:04
So once again let's grab the line tool,
03:06
let's close off the bottom of this
03:08
and then let's select the endpoint
03:10
and create a horizontal line coming all the way back.
03:15
Next we want to finish off the blade profile.
03:18
I'm going to use a tangent constraint
03:20
And go ahead and select these two.
03:23
We'll finish the sketch and create a new extrude
03:26
to make sure that we have the correct thickness.
03:27
Let's bring back the original blade. Select extrude,
03:30
grab our profile
03:32
including the salt tooth
03:34
and we can extrude it to the other side. Using to object
03:39
this is going to be a new body inside of our current component.
03:43
Once again, we can hide the blade,
03:45
expand our sketches
03:47
and we can hide our origin.
03:49
Next we want to extrude out our saw blade
03:52
so we're going to go ahead and turn this
03:54
around and make sure that we extrude through all.
03:58
Now that we have this feature. We can go ahead and hide the sketch.
04:01
Go to our linear or rectangular pattern
04:04
and select the option to pattern a feature.
04:07
This will be our second extrude.
04:08
Cut the direction will be along the edge of the blade.
04:12
We're going to use a spacing option,
04:14
giving it a two millimeter spacing and that
04:17
should perfectly line up each of the teeth.
04:19
We now just need to increase the number and we can do that
04:22
by grabbing on this manipulator and dragging it toward the plus direction.
04:27
We can also manually increment this,
04:29
giving it a number of teeth that we think is correct.
04:32
In this case let's try 55 and see how close we get.
04:35
You can see that we still need a few more. So let's increase this to 65
04:39
looks like we have one too many. So we'll go down to 64,
04:43
we're going to say, okay,
04:45
and now we've created a new version of the saw blade with a different tooth pattern.
04:50
If we go back to the top level of the design,
04:52
we can bring back the blade holder and we can see our new version of the saw blade.
04:56
We can also hide our new blade and show the old blade with smaller teeth.
05:01
If we make any mistakes, remember that,
05:03
we can always go back and modify our sketches.
05:05
So for example, if we edit this sketch,
05:08
double click the mouse wheel to bring it in view,
05:11
we can determine that this edge does not need
05:13
to be vertical by selecting it and hitting.
05:15
Delete.
05:16
Then we can determine that this edge does not need to be perpendicular.
05:20
This allows us to drag these around.
05:22
We also need to make sure we get rid
05:24
of that perpendicular constraint and make that line horizontal.
05:26
Again.
05:28
We're gonna go ahead and make this front edge vertical,
05:30
and then we'll drag it down until we're at the appropriate angle.
05:34
We can see that two
05:36
is about two of the original teeth and I'm going to dimension this vertical line
05:40
so that it's 1.25 mm.
05:43
Next we'll finish the sketch and all the patterns should update properly.
05:48
Once again,
05:49
we could go back and forth between our new blade and
05:51
the old blade and just see the difference between the two.
05:54
Once we're done with this example,
05:56
let's make sure that we do go back to a front view and save the design.
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