Utilize Place Views

00:02

Utilize Place views.

00:04

After completing this video, you'll be able to override dimension style, create required drawing views on a 2D drawing,

00:11

display an assembly fully retracted and fully extended in a drawing,

00:15

create and edit documentation using IPN files,

00:18

validate a drawing after a model update,

00:21

recall when a model needs to be modified versus drawing annotation change,

00:25

and describe how to update an iProperty from a model to reflect on the drawing.

00:31

Inside Inventor, we want to begin by opening up two supplied datasets,

00:36

Engine Mark 2.IAM, which is in the assembly subfolder under the Engine Mark 2 subfolder,

00:42

and Engine mark 2-1.IPN presentation file in the same folder.

00:46

In this video, we're going to focus on using detailed drawings and view representations and position representations in those drawings.

00:54

We want to begin by expanding the Representations folder as well as expanding View and Position Representations.

01:01

We're going to be using the internals representation for our view

01:05

and the top and bottom representations for the position.

01:08

This is going to allow us to create an overlay view inside of our detailed drawing.

01:13

We're also going to be using the IPN or Inventor presentation file.

01:17

This is a great way to create exploded views and save snapshot views that can be used in our detailed drawing.

01:23

Inside of our engine file, let's go ahead and start a new detailed drawing.

01:27

From the Drawings option, we'll use the empty template and create our own views.

01:32

We'll start with a base view, make sure that we have a scale that's easy to see, in this case 4:1,

01:38

we're going to use the Associative option for our design view, and we'll make sure that we select Internals and with our position view at the top.

01:47

Using the Associative option for our design view means that any time we make a change to the design view in our assembly,

01:54

the drawing view will automatically update.

01:56

Let's go ahead and say OK, and then we're going to move the position of this view up a little bit.

02:01

Next, let's create a projected view.

02:03

We'll create one off to the right, and we're going to go ahead and create an isometric view.

02:08

Right click and create.

02:10

From here, we now want to talk about creating an overlay view.

02:14

An overlay view is a way for us to show different position representations on the same detailed drawing.

02:19

In the case of our engine, we want to show the piston in its upper and lower positions as it travels through its rotation.

02:26

So we're going to do this on our side view.

02:28

Remember that we have the associative option set for our design view.

02:33

When we go to overlay and we select a view to apply the overlay to,

02:37

note that the Associative option is automatically checked because it's inheriting this from the parent view.

02:43

We're going to make sure that we are using the internals design view as well as the bottom position view.

02:49

We're also going to inherit the style from the base view and say OK.

02:53

This puts our design in the lower position with dash lines for all the components.

02:58

In some instances you may decide that some components need to be hidden.

03:03

We can always do this by going back to our assembly and making changes specifically in the view representation.

03:09

For example, this bearing on the end really isn't needed for what we're doing.

03:13

We can find the bearing by going down to the clutch bell and finding the first STNSKF bearing.

03:19

We're going to right click and change its visibility, and then we're going to go back to our detailed drawing.

03:25

Our detailed drawing view is now out of date.

03:28

So if we select our view, right click and update the model, we'll select OK to update our model

03:33

and OK for the save and OK one more time to open up both views and notice that the bearing is now missing from all of our views.

03:41

The bearing is removed because we had the associative option on for our view representation.

03:46

Next, let's take a look at a couple of other views.

03:49

We've got section views, detailed views, breakout views,

03:53

and several other view types that we may use on a detailed drawing.

03:57

Let's first go ahead and take a look at a breakout view.

03:60

The breakout view, unlike a section view, will apply directly to the view we're placing it on.

04:05

In this case, if we use a breakout view on our original base view,

04:08

we're prompted to start a new sketch.

04:11

In this case, I'm going to begin creating some sketch lines that are going to go through a portion of our engine assembly.

04:17

Once we close the profile and finish the sketch, this is going to allow us to either take this up to a specific point in our assembly.

04:24

We can take it to the sketch itself, to a specific hole, or through the entire part.

04:30

From here, we can also make some additional selections.

04:33

But once we select OK on our breakout view, notice that it's cut through a portion of this design.

04:39

Once again, the breakout and break views are going to apply directly to the view we've selected,

04:44

unlike views like a section view or projected view, which will actually create a new view in our drawing.

04:50

Let's talk about a couple of other things in detailed drawings.

04:53

Next, let's go to our annotations and start to add dimension.

04:57

If we want to see what the diameter of the piston is, we can add a simple dimension to the drawing.

05:02

But in some cases we may need to modify the dimension or the display here.

05:07

What we see on the screen is the ability to add simple symbols, notes, and text to any detailed drawing annotation.

05:15

In this case, we want to talk about precision and tolerance.

05:19

Precision and tolerances are needed, especially for manufacture parts,

05:23

so we can understand how big or small those parts can be during the manufacture process.

05:27

In this case, the piston may use a symmetric tolerance method,

05:32

and we want to make sure that our units and our primary tolerance have enough decimal places to account for any tolerance values.

05:39

In this case, let's say that it needs to be ±.001 and we can say OK.

05:45

If we zoom in, we can see that our dimension is listed as .551 ± .001.

05:52

Any changes needed can be double clicked and modify our tolerance value directly inside of the edit dimension dialogue.

05:59

Making sure that we are using the correct tolerance method and styles is an important step in the process.

06:05

Keep in mind that our styles and standards will be able to dictate some of this information for us.

06:11

For example, the precision on our primary units and our primary tolerances.

06:15

Let's go ahead and say OK, and go back to the entire drawing sheet.

06:19

In some cases, we need to consider modifications at the drawing level,

06:24

while in other cases we need to consider modifications at the part or assembly level.

06:28

When we have dimensions on a detailed drawing,

06:31

if the dimensions need to be increased or decreased, that's a change that needs to happen at the part or assembly level.

06:39

While we do have the option to double click on a dimension and override the specific dimension displayed,

06:44

it's always a good idea to make sure that our 3D model is accurate and up to date.

06:49

So making changes to those dimensions should happen at the part or assembly level,

06:54

while making changes to things like notes and annotations can happen directly at the detailed drawing level.

06:59

In addition to notes and annotations, you may find the need to add a note or an annotation that is linked to a specific parameter.

07:07

In some cases, you may want to grab standard or custom iProperties from the part or assembly.

07:13

You can find these by changing our type, taking a look at the specific value, for example material,

07:19

and then putting that as a note inside of our detailed drawing.

07:23

We can see here that the note comes up as default, and in this case it's using the default material because no material was added.

07:30

But being able to modify that back at the assembly level allows us to go back into our design,

07:36

select the top level of our design, and change the material for all components in this design.

07:42

In this case, we're going to leave the engine assembly alone,

07:45

but just keep in mind that our custom and our standard iProperties can be linked between our parts assemblies and our detailed drawings.

07:53

Any changes to the part or assembly level will be able to be updated at our detailed drawing level.

07:58

There are many ways in which we can link information from our parts assemblies and our detailed drawings together,

08:04

and these are just a few.

08:06

Make sure that you do spend a little bit of time to get comfortable with using position representations

08:11

and view representations in our overlay views and detailed drawings,

08:15

and also understand how to create things like breakouts and section views,

08:18

as well as use annotations, dimensions and modify your dimension styles.

08:23

So when we're talking about IPN files or Inventor presentation files,

08:28

using the presentation files as an exploded view in a detailed drawing is fairly easy.

08:33

But it's important to note that our presentation files also reference our view representations.

08:39

If we go to our scene on the right hand side and select representations,

08:42

it's important to make sure that we're using the primary design view.

08:46

If we happen to use something like the internal design view, which often times gets automatically added,

08:51

we would need to make sure that we reset the view representation and that we update all of our snapshot views.

08:58

Keep in mind that each of these views can be renamed so they're easier to access when we're in a detailed drawing.

09:04

Let's go ahead and rename View 1 to Home View.

09:09

Next, we're going to create a new detailed drawing or go back to our other detailed drawing and add it to a new sheet.

09:16

In this case, we're on sheet 2 and we're going to start base view.

09:20

When we're looking at the base view, we want to make sure that we're using the IPN file and not the assembly file.

09:25

When we do this, we also want to make sure that we are accessing the correct snapshot, in this case the one we have called Home.

09:32

Here we also have an associative option like we did before.

09:36

This means any changes to the view representation will automatically be updated in the drawing.

09:41

Let's go ahead and change the scale to 4:1 and say OK.

09:45

Notice that when we look at this snapshot, it's only showing the internals of the engine.

09:51

It is important that we go back to our presentation file

09:54

and note that the representation has changed based on our assembly.

09:57

Even though our snapshot views are showing the entire assembly,

10:01

we do want to make sure that we go into our representations in the scene,

10:04

double check that we are using primary, and make sure that everything is updated.

10:09

Once again, the associative option can be extremely handy in drawings,

10:13

but sometimes it can cause problems having view representations update when we don't want them to.

10:18

We can see here that the scale is a little bit big,

10:21

but hopefully for the purposes of this video we can see how to use those IPN snapshot views in a detailed drawing.

10:27

As always, you can double click on the view, make changes to the scale and have it update properly.

10:33

At this point we've talked about a lot of different topics for detailed drawings,

10:37

but the important take away here is to make sure that we understand that data from our parts and assemblies,

10:43

such as view representations and our position representations,

10:47

in addition to metadata like iProperties, can be pulled into our detailed drawings and set to associative so that they update automatically.

10:56

We also have the option to make changes to things like annotations and dimensions directly in detailed drawings,

11:02

but in some cases we want to make those changes at the part or assembly level,

11:06

while in other cases we can make changes directly at the drawing level.

11:10

Make sure that you do play around with all these options, including creating your own breakout views, overlay views,

11:17

detail views, section views, as well as the base views and projected views and detailed drawings.